Owner's manual

Tool Control Functions
Chapter 20
20-18
It is possible to alter or generate values in the tool offset tables (see section
3.1) by using the programming feature discussed in the following section.
It is possible to enter data in the offset tables by programming the correct
G10 c ommand. The following section describes the use of the G10
commands.
Important: Note that G10 blocks may not be programmed when cutter
compensation is active.
A G 10 code used to modify a tool offset table value will only change the
value in the table. If that offset value is c urrently being used by the
control, the active offset value will not be updated until the offset value is
called a gain from the table using a D or an H--word.
Any values entered in an offset table using the G10 command while the
control is in incremental mode (G91), are added to the currently existing
offset data. Any values entered in an offset table using the G10 command
while the control is in absolute mode (G90), are used to replace the
currently existing offset data.
The following is a representation of the basic format for modifying the
offset tables.
G10 L(10 -13) P__ R__;
Where : Is :
L(10-13)
Designates thedefinitionsoftheotherparameter databeing usedin the G10
block. The L--worddefinesthe otherparametersas describedin Table21.A.
P
seeTable21.A
R*
seeTable21.A
* When setting tool length axis values, R can be replaced with the name of the axis (typically X, Y, or Z). Axis
names are always used by the control when offset tables are back ed up by the control. If y ou use an R to set
a tool length value, it is appliedto t he axis currently selected as the tool length axis. See page 20-9 for
details on selecting the activ e tool length axis.
Table 21.A
Parameters for Modifying t he Tool Offset Tables
Value for the
L Parameter
Parameter Definition
P R,X,Y,Z
L10
Geometrytable
OffsetNumber toollength geometryvalue
L11
Wear table
OffsetNumber toollength Wear table
20.4
Programming Alterations of
the Offset Tables (G10L10 -
G10L13)