Specifications

I Alarms
Program Errors (P)
I - 63
P132 Spindle rotation speed S=0
Details
No spindle rotation speed command has been issued.
Remedy
- Correct the program.
P133 Illegal P-No. G96
Details
The illegal No. was specified for the constant surface speed control axis.
Remedy
- Correct the parameter settings and program that specify the constant surface speed control
axis.
P134 G96 Clamp Err.
Details
The constant surface speed control command (G96) was issued without commanding the
spindle speed clamp (G92/G50).
Remedy
Press the reset key and carry out the remedy below.
- Check the program.
- Issue the G92/G50 command before the G96 command.
- Command the constant surface speed cancel (G97) to switch to the rotation speed com-
mand.
P140 No spec: Pos compen cmd
Details
The position compensation command (G45 to G48) is out of specifications.
Remedy
- Check the specifications.
P141 Pos compen during rotation
Details
Position compensation was commanded during the figure rotation or coordinate rotation com-
mand.
Remedy
- Correct the program.
P142 Pos compen invalid arc
Details
Position compensation cannot be executed with the issued arc command.
Remedy
- Correct the program.
P150 No spec: Nose R compensation
Details
- Tool radius compensation commands (G41 and G42) were issued though they are out of
specifications.
- Nose R compensation commands (G41, G42, and G46) were issued though they are out of
specifications.
Remedy
- Check the specifications.
P151 Radius compen during arc mode
Details
A compensation command (G40, G41, G42, G43, G44, or G46) has been issued in the arc
modal (G02 or G03).
Remedy
- Issue the linear command (G01) or rapid traverse command (G00) in the compensation
command block or cancel block.
(Set the modal to linear interpolation.)
P152 No intersection
Details
- In interference block processing during execution of a tool radius compensation (G41 or
G42) or nose R compensation (G41, G42, or G46) command, the intersection point after one
block is skipped cannot be determined.
- The compensation amount cannot be calculated during the tool radius compensation for 5-
axis machining (G41.2,G42.2).
Remedy
- Correct the program.
P153 Compensation interference
Details
An interference error has occurred while the tool radius compensation command (G41 or G42)
or nose R compensation command (G41, G42 or G46) was being executed.
Remedy
- Correct the program.
P154 No spec: 3D compensation
Details
A three-dimensional compensation command was issued though it is out of specifications.
Remedy
- Check the specifications.
P155 Fixed cyc exec during compen
Details
A fixed cycle command has been issued in the radius compensation mode.
Remedy
- Issue a radius compensation cancel command (G40) to cancel the radius compensation
mode that has been applied since the fixed cycle command was issued.
P156 R compen direction not defined
Details
A shift vector with undefined compensation direction was found at the start of G46 nose R
compensation.
Remedy
- Change the vector to that which has the defined compensation direction.
- Change the tool to that which has a different tip point No.