Specifications

55
Southwestern Industries, Inc.
TRAK LPM Programming, Safety, & Operating Manual
screen where you may choose to have a fixed amount of material taken per peck or have
the cutter move up just enough to break the chip before continuing to feed down.
RPM: is the spindle RPM for the event. INC SET will use the RPM of the previous
event.
Z Feedrate: is the drilling feedrate
Tool #: is the tool number you assign
If a bore is selected and entered, you can change the tool path of the bore from the default
tool path of feeding in and feeding out at the programmed rpm. After selecting Bore, use
the cursor key to move over the prompt again. The blue ? will appear. Press HELP to be
able to change the tool path to feed down, position away from the cut and then rapid out
of the hole. The following prompts will appear:
Angle: is the angle from 3 o’clock CCW to the location of the cutting insert
Retract Dist: is the distance the cutting tool will retract towards the center of the bored
hole.
8.3 BOLT HOLE Events
This event allows you to program a bolt hole pattern without needing to compute and
program the position of each hole.
Prompts for the Bolt Hole event:
Drill=1, Bore=2, Tap = 3: selects whether the hole is to be drilled or bored
Once the bore is selected and entered, you can change the tool path of the bore from the
default tool path of feeding in and feeding out at the programmed rpm. After selecting
Bore, use the cursor key to move over the prompt again. The blue ? will appear. Press
HELP to be able to change the tool path to feed down, position away from the cut and
then rapid out of the hole.
# Holes: is the number of holes in the bolt hole pattern
X Center: is the X dimension to the center of the hole pattern
Y Center: is the Y dimension to the center of the hole pattern
Z Rapid: is the Z dimension to transition from rapid to feed
Z Begin: appears for tapping only, this is the top of the work piece
Z End: is the bottom of the hole
Radius: is the radius of the hole pattern from the center to the center of the holes
Angle: is the angle from the positive X axes (that is, 3 o'clock) to any hole; positive
angle is measured counterclockwise from 0.000 to 359.999 degrees, negative angles
measured clockwise.
Pitch: is the pitch of the tap that is used if the Tap option is chosen.
Warning!
The boring tool you are using must be placed in the spindle
consistently when using this feature. If you place the boring tool
in the spindle 180º from how you set the tool up the first time, the
cutting tool will crash into your workpiece.