Specifications

152
Southwestern Industries, Inc.
TRAK LPM Programming, Safety, & Operating Manual
Tool Numbers and Tool Changes: the format of the tool number is from T1 to T99.
During program run, the ProtoTRAK will rapid to home for a tool change and pause for
the tool to be loaded manually and the operator to press GO.
Feed Rates: the ProtoTRAK is programmed in inches (or mm) per minute using the 'F'
address.
Spindle Speed: Defined by the ‘S’ address, followed by the speed in Revolutions Per
Minute.
File Name: use the .CAM extension so the ProtoTRAK PMX will recognize the file as a
CAM file and convert it into ProtoTRAK events when it is opened. File names may
include up to 20 alpha-numeric characters.
14.13.2 Convertible G-Codes for CAM Converter
The following G-codes may be used in a CAM file that you want to have converted to a
ProtoTRAK program. G Codes that are not on the list below have no correspondent
operation in the ProtoTRAK events and will be ignored when the program is converted.
If a G-Code is essential to your program and you do not see it here, you can do one of
two things.
1. Convert the file from CAM to ProtoTRAK and add an event to the resulting
ProtoTRAK program.
2. Run the program as a GCD file (See Section 14.11).
G Code
Description
Acceptable Format
Notes
G00
Position at maximum feedrate
G00 X0.0 Y0.0 Z0.0
G01
Linear Interpolation
G01 X0.0 Y0.0 Z-1. F15.
F = Feedrate in Inches per
minute
G02
Circular Interpolation
(Clockwise)
G02 X1. Y2. I0. J2.
I & J define the X and Y
centerpoints respectively,
incremental from the
starting point of the arc.
G03
Circular Interpolation
(Counter-clockwise)
G03 X2. Y0. I2. J0.
G20
Input in Inch
G20
G21
Input in Metric
G21
G40
Cutter compensation cancel
G40
G41
Cuttter compensation left
G41
G42
Cutter compensation right
G42
G80
Canned cycle cancel
G80
G81
Drilling cycle, spot boring
G81 X0. Y0. Z-1. R.1 F15.
Z = final depth, R = rapid
position
G82
Drilling cycle, counter boring
G82 X0. Y0. Z-1. R.1 P500 F15.
P = dwell time in
milliseconds
G83
Peck drilling cycle
G83 X0. Y0. Z-1. Q.125 R.1 F15.
Q = depth of peck
G84
Tapping cycle
G84 X0. Y0. Z-2. R.1 S300 F15.
For machines with
programmable spindle only.
S defines RPM,
Pitch = F / S
G85
Boring cycle
G85 X0. Y0. Z-1 R.1 F15.
G86
Boring canned cycle with
retract
G86 X0. Y0. Z-2. R.1 A35. Q.020
P300 F15.
A = Angle of boring head.
Q = Retract distance from
wall of hole