2009

2 Click the Extrude tool to display the Extrude dialog box.
If there is only one profile in the sketch, it is automatically selected.
If there are multiple profiles, on the Shape tab, click Profile, and then
select the profile to extrude. Use Select Other to cycle through selectable
geometry, and then click to select.
3 In Output, click either the Solid or Surface button.
For base features, only Surface is available for open profiles. For assembly
extrusions, only Solid is available.
4 Click the Join, Cut, or Intersect button.
For assembly extrusions, only the Cut operation is available.
5 In Extents, on the drop-down menu, select the method to terminate the
extrusion. Some methods are not available for base features.
Distance: Enter the distance of the extrusion.
To Next: Click the direction of the extrusion.
NOTE To Next is not available for assembly extrusions.
To: Click a sketch point, work point, model vertex, work plane, or the
End termination plane.
From-To: Click the Start and End termination planes.
By default, the extrusion terminates on the maximum-distance plane
To and From-To extents: Click Minimum Solution to terminate on the
nearest-distance plan.
All: Click the direction of the extrusion or to extrude equally in both
directions.
NOTE If termination options are ambiguous, such as on a cylinder or irregular
surface, click the More tab, and then use Flip to specify direction
6 On the More tab, enter a Taper angle, if necessary.
In the graphics window, an arrow shows the taper direction.
Click OK.
The sketch is extruded.
Extrude Features | 59