2009
Table Of Contents
- Contents
- 1 Introducing Autodesk Inventor
- 2 Creating Sketches
- 3 Working with Sketched Features
- 4 Creating and Editing Placed Features
- 5 Creating and Editing Work Features
- 6 Using Projects to Organize Data
- 7 Managing Assemblies
- 8 Placing, Moving, and Constraining Components
- 9 Creating Assemblies
- 10 Analyzing Assemblies
- 11 Using Design Accelerator
- 12 Setting Up Drawings
- 13 Creating Drawing Views
- 14 Annotating Drawings
- Annotation Tools
- Using Styles to Format Annotations
- Working with Tables
- Creating Dimensions In Drawings
- Controlling Dimension Styles
- Placing Center Marks and Centerlines
- Adding Notes and Leader Text
- Using Hole and Thread Notes
- Working with Title Blocks
- Working with Dimensions and Annotations
- Printing Drawing Sheets
- Plotting Multiple Sheets
- Tips for Annotating Drawings
- 15 Using Content Center
- 16 Autodesk Inventor Utilities
- Index
■ Centerline
■ Centerline Bisector
■ Centered Pattern
Add center marks and centerlines before adding drawing dimensions. You can
dimension to the ends of the center marks and centerlines and maintain
correct gaps.
You can add center marks to extruded circular cut features and include these
cuts in a hole table. Add the center marks to the hole table style so they are
recognized in the drawing.
TRY IT: Add center marks, circular cuts, and hole features to the hole table
style.
1 Open a drawing file.
2 Click Format ➤ Style and Standard Editor.
3 In the browser pane of the Style and Standard Editor dialog box, expand
Hole Table and double-click the style to edit.
4 Click the Options tab. In the Default Filters (View) box, in the Included
Features category, select hole features, circular cuts, and center marks.
5 Click Done and then click Yes to save edits.
Now, hole features, circular cuts, and center marks can be selected for inclusion
in a hole table.
In addition to manually placed centerlines, you may be able to use automated
centerlines in a drawing view. When you set up a drawing, use options in
document Settings to define the default criteria for adding automated
centerlines. If you want to use them in all drawings, set them in drawing
templates. You specify the types of features to receive centerlines and if the
geometry is normal or parallel projection, as well as thresholds to exclude
circular features smaller or larger than a specified radius and smaller than a
minimum angle.
Adding Notes and Leader Text
Use the Text tool to add general notes to a drawing. General notes are not
attached to any view, symbol, or other object in the drawing.
248 | Chapter 14 Annotating Drawings