Programming instructions

ADT-CNC4620 Programming Manual
- 23 -
reach the end point at the same time.
Either or both instruction addresses X(U) and Z(W) can be omitted. If one is
omitted, the coordinates of the start point and end point of the axis are consistent; if
both are omitted, the start point and end point are in the same position.
The fast moving speed of X axis and Z axis are set by X axis fast moving speed
and Z axis fast moving speed respectively, and the actual moving speed can be adjusted
with the fast ratio key on the panel of the machine tool.
The maximum speed that the machine tool actually can reach depends on the actual
condition of the machine tool and the motor. For detailed parameters, please refer to
the manual of the machine tool.
G00 is modal instruction, and can be omitted if next block is same.
G00 can be abbreviated to G0, which is equivalent to G00.
If X axis and Z axis are moved at the same time, note whether the tool is in safe
area to avoid bump.
For example: the tool moves from point A to point B quickly.
Z axis X axis
G0 X20 Z25; (A coordinates)
G0 U-8 W-14; (A→B)
3.2.2. Linear interpolation G01
Instruction format: G01 X(U)_ Z(W)_F_;
X(U) /Z(W): absolute or relative coordinates of the end point.
F : cutting feeding speed
Instruction function: G01 instruction makes the tool arrive at the position of specified point
along the connection line from current point to the point specified by X(U), Z(W) at
specified speed. The motion track is a straight line from the start point to the end point. F
instruction value is the vector synthetic speed of instantaneous speed of X axis and Z axis,
and the actual cutting feeding speed is the product of feeding ratio and F instruction value.
Once executed, F instruction value is maintained until new F instruction value is executed.
For example:
G01 X60.0 Z-25 F200; (absolute value programming)
G01 U20.0 W-25.0; (relative value programming)