Manual
Table Of Contents
- Controls of the 3500i
- Manual Information
- Introduction
- Machining Fundamentals
- Manual Data Input
- Tool Management
- 4.1 Tool Table
- 4.2 Tool Data
- Program Management
- Conversational Editing
- Programming: Canned Cycles, sub-programs
- 7.1 Explaining Basic Cycles
- Round/Chamfer
- Rapid
- Line
- Arc
- Dwell:
- Plane Selection
- Reference Point Return:
- Fixture Offset (Work Coordinate System Select):
- Unit (Inch/MM)
- Dimension (Abs/Inc)
- Absolute Zero Set
- Block Form
- Temporary Path Tolerance
- System Data
- FeedRate
- FeedRate (4th-Axis)
- Spindle RPM
- M - Functions
- Tool Definition and Activation
- Repeat Blocks
- 7.2 Canned Cycles
- 7.3 Probing Cycles
- 7.4 Sub-programs
- 7.1 Explaining Basic Cycles
- Drawing Programs
- Running a Program on the Machine
- CAM: Programming
- 10.1 CAM Programming
- CAM Mode
- Recommended CAM Programming Sequence
- CAM Mode Mouse Operations
- CAM Mode Screen
- Activating CAM Mode
- Creating a New Program
- Tool Path Data Input
- Quick Coordinate Entry
- Job Setup: Basic tab
- Job Setup: Advanced tab
- Comment Tab
- Block Form: Basic tab
- Comment Tab
- Drilling Cycle:
- Drilling dialogue:
- Mill Cycle
- Pocket Cycle
- Pocket Finish Cycles
- Engraving Cycle
- Program Directive
- Modifying Toolbar
- Viewing Tools
- CAM Mode buttons
- CAM Setup
- Geometry
- DXF Import Feature
- Modifying Tools
- Shapes
- Tool Table
- Tool Paths
- CAM Example 1
- CAM Example 2
- 10.1 CAM Programming
- G-Code Edit, Help, & Advanced Features
- 11.1 G-Code Program Editing
- 11.2 G-Code and M-Code Definitions
- 11.3 Edit Help
- 11.4 Advanced Programming
- SPEED
- M - Functions
- Order of Execution
- Programming Non-modal Exact Stop:
- In-Position Mode (Exact Stop Check):
- Contouring Mode (Cutting Mode) :
- Setting Stroke Limit:
- Return from Reference Point:
- Move Reference from Machine Datum:
- Modifiers
- Block Separators
- Tool Offset Modification
- Expressions and Functions
- System Variables
- User Variables
- Variable Programming (Parametric Programming)
- Probe Move (G31)
- Conditional Statements
- Short Form Addressing
- Logical and Comparative Terms
- File Inclusion
- 11.5 Four Axis Programming
- Software Update
- Off-Line Software
ACU-RITE 3500i 405
11.4 Advanced Programming
Variable Programming Examples
This program uses common variables in the range of #50 to #149. The
program mills a pocket with a three-degree draft angle on the
sidewalls. The dimensions at the bottom of the pocket are:
15.5730 (X axis) x 13.8850 (Y axis). The pocket is 1.0000 in. deep.
The tool begins at the upper-left corner of the pocket and at full depth.
Part Zero is set in the center of the pocket.
Example 1:
O 28 * 3-Deg. Drft Pkt
G90 G70 G0 G17 #101 = 1
T0 #102 = 2
Z0 #103 = 3
X0 Y0 #104 = 4
T1 #119 = 100
X-7.7865 Y6.9425 * MOVE TO UP-LEFT CORNER
Z.5
G1 Z-1 F10 * FEED TO DEPTH
F40
#101 = 15.5730 * LENGTH (X) OF POCKET
#102 = 13.8850 * WIDTH OF POCKET
#103 = .0200 * DESIRED "STEP-UP" IN Z AXIS
#104 = (#103*TAN(3)) * CALCULATE "STEP-OVER" IN X-Y
AXES
M98 P100 * CALL sub-program 100
T0
G90 G0 Z0