Manual

ACU-RITE 3500i 301
10.1 CAM Programming
Mill Cycle
The Mill Cycle tool path is used to generate a milling cycle from a
defined shape. The cycle rapids to the X Start, Y Start point, rapids to
the Start Height and then feeds to the Z Depth using the Z Feed and
mills the selected shape. The cycle is completed and rapids up to the
Start Height and returns to the X End, Y End location. Activate a tool
prior to a Mill Cycle so the CNC knows the tool diameter.
Basic tab:
 Start Height: Enter the absolute Z position to which the CNC rapids
before feeding into the work piece.
 Z Depth: Enter the absolute depth of the finished pocket.
 Depth Cut: Enter the Z-axis increment used for each pass.
 Finish Stock: Enter the finish-stock amount per side (including
bottom).
 Entry Type: Choose Line Tangent, Line Perpendicular, Arc Tangent,
Line Arc Tangent or None for the entry move.
 Line Tangent - The tool enters the contour in a line move tangent
to the first move of the contour.
 Line Perpendicular - The tool enters the contour in a line move
perpendicular to the first move of the contour.
 Arc Tangent - The tool enters the contour in an arc move of a given
radius and angle and tangent to the first move of the contour.
 Line Arc Tangent - The tool enters the contour in an arc move of a
given radius and tangent to the first move of the contour.
 None - Entry move is ignored.
 Length (Line Tan, Line Per): Enter the length of the entry move.
 Angle (Arc Tan): Enter the angle of the entry arc.
 Radius (Arc Tan, Line Arc Tan): Enter the radius of the entry arc.
 Exit Type: Choose Line Tangent, Line Perpendicular, Arc Tangent,
Line Arc Tangent or None for the exit move.
 Line Tangent - The tool exits the contour in a line move tangent to
the last move of the contour.
 Line Perpendicular - The tool exits the contour in a line move
perpendicular to the last move of the contour.